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标题: 【推荐】surf introduce [打印本页]

作者: tommy221 时间: 2003-3-2 16:44
标题: 【推荐】surf introduce
CH1 Design Philosophy
Design Planning

            Start-up
               Delivery of Design Requirements
            Development Tools

When To Use Pro/SURFACE

            External Influences
            Direct Influences
                Internal Influences
          

Applying Design Philosophy to a Component Shape
               Hair Brush Handle

Summary

CH2 Pro/SURFACE Model
            Construction

Complex Modeling Styles

        [$#8226] Style1:Known geometric shapes
               added to or subtracted from
               one another

        [$#8226]Style2:Smooth outer profile or
               curvature all around

        [$#8226]Style3:Blinded shapes

Summary

Known geometric shapes added to or
               subtracted from one another



步驟1  建立新零件,並輸入零件名稱
     &nbsp

art → Create → [輸入零件名稱 Sruf_1]

步驟2  建立Datum Plane
      Create → Datum → Plane → Default

步驟3  建立一條Curve特徵
      Create → Datum → Curve → Sketch | Done
      → [選DTM2為sketch plane] → Okay
      → [選DTM3為Bottom refer plane ]
      → [進入Sketcher模式,繪製如圖1之剖面] → Done
      → OK → [完成Datum Curve之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖2所示]

  圖 1

  圖 2

步驟4  建構圓柱面特徵
      Create → Surface → New → Sweep | Done
      → Select Traj → [選剛才建構之curve] → Select | Done
      → Okay → Open Ends | Done
      → [進入Sketcher模式,繪製如圖3之剖面] → Done
      → OK → [完成Surface之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖4所示]

圖 3


圖 4

步驟5  Copy剛才完成的Surface Feature
      Create → Copy → Mirror | Select | Independent | Done
      → [選剛才完成的Sweep surf] → Done Sel → Done
      → [選要鏡射的平面(DTM3)] → [零件如圖5所示]


圖 5

步驟6  將兩個曲面merge
      Create → Surface → Merge → [選取兩個曲面]
      → Flip → Okay → Flip → Okay → Done sel
      → Done → [零件如圖6所示]

  圖 6

步驟7  建構倒圓角特徵
      Create → Surface → New → Fillet | Done
      → Simple | Done → Variable | Edge Chain | Done
      → [選取兩個圓柱面交界處] → Done
      → [在中間再加入一點] → Done → [給圓角值1]
      → [給圓角值1] → [給圓角值1.5] → OK
      → [完成倒圓角Surface之特徵]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖7所示]


圖 7

步驟8 建構矩形面特徵
      Create → Surface → New | Done → Extrude
      → One side / Open Ends / Done → [選DTM2為sketch plane]
      → Flip → Okay → [選DTM3為Top refer plane ]
      → [進入Sketcher模式,繪製如圖8之剖面] → Done
      → Blind | Done → [輸入8之深度(Depth)] → OK
      → [完成Surface之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖9所示]


圖 8

  圖 9

步驟9  將兩個曲面merge
      Create → Surface → Merge → [選取兩個曲面]
      → Flip → Okay → Flip → Okay → Done sel
      → Done → [零件如圖10所示]


圖 10

步驟10  建構倒圓角特徵
      Create → Surface → New → Fillet | Done
      → Simple | Done → Variable | Edge Chain | Done
      → [選取圓柱面與矩形面交界處] → Done
      → [增加新的半徑值的點共增加8個點] → Done
      → [給兩種圓角值,短邊給1,長邊給1.5] → OK
      → [完成倒圓角Surface之特徵]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖11所示]

  圖 11

步驟11  建構Trim特徵
      Create → Surface → Trim → Extrude | Solid | Done
      → [選要被trim掉的surface] → One side | Done
      → Make Datum → Offset → [選DTM1] → Enter Value
      → [輸入-30之Offset距離] → Done → Okay
      → [選DTM2為Top refer plane ]
      → [進入Sketcher模式,繪製如圖12之剖面] → Done
      → OK → [完成Surface之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖13所示]

圖 12

圖 13

步驟12  建構薄殼特徵
      Create → Solid → Protrusion → Use Quit/Thin/Done
      → [選取surface特徵] → Flip → Okay
      → [輸入薄殼厚度0.15] → OK
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖14所示]

  圖 14



Smooth outer profile or curvature all around


步驟1 建立新零件,並輸入零件名稱
     &nbsp

art → Create → [輸入零件名稱 Sruf_2]

步驟2 建立Datum Plane
      Create → Datum → Plane → Default

步驟3 建構圓柱Surface特徵
      Create → Surface → New | Done→ Extrude
      → One side / Open Ends / Done → [選DTM2為sketch plane]
      → Flip → Okay → [選DTM3為Top refer plane ]
      → [進入Sketcher模式,繪製如圖1之剖面] → Done
      → Blind | Done → [輸入20之深度(Depth)] → OK
      → [完成Surface之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖2所示]


圖 1


圖 2

步驟4 建構圓弧面特徵
      Create → Surface → New | Done → Extrude
      → Both side / Open Ends / Done → [選DTM3為sketch plane]
      → Okay → [選DTM2為Top refer plane ]
      → [進入Sketcher模式,繪製如圖3之剖面] → Done
      → Blind | Done → [輸入12之深度(Depth)] → OK
      → [完成Surface之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖4所示]


圖 3

圖 4

步驟5  建立底面規跡的 Curve特徵
      Create → Datum → Curve → Intr [$acute] Surf | Done
      → Whole → [選圓柱面] → Whole → [選圓弧面]
      → [產生交線]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖5所示]


圖 5
步驟6  建構二個Datum Plane特徵
      Create → Datum → Plane → Through → [選圓柱面的軸心]
      → Angle → [選DTM3] → Done → Enter value → [給60度]
      → [同上的步驟在Enter value 給-60度] → Done
      → [完成兩個Datum Plane之建構] → [零件如圖6所示]


圖 6

步驟7  建構point特徵
      Create → Datum → Point → Curve [$acute] Surf
      → [選前半邊的curve] → [選DTM4] → Done sel
      → Curve [$acute] Surf → [選前半邊的curve] → [選DTM5]
      → Done sel → Curve [$acute] Surf → [選後半邊的curve]
      → [選DTM4] → Done sel → Curve [$acute] Surf
      → [選後半邊的curve] → [選DTM5] → Done sel → Done
      → [完成四個point之建構] → [零件如圖7所示]

圖 7

步驟8  建立一條頂面Curve特徵
      Create → Datum → Curve → Sketch | Done
      → [選DTM3為sketch plane] → Okay
      → [選DTM2為Top refer plane ]
      → [進入Sketcher模式,繪製如圖8之剖面] → Done
      → OK → [完成Datum Curve之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖9所示]

圖 8

圖 9
步驟9  建立另二條頂面Curve特徵
      [同步驟8分別建構出通過 PNT2,PNT0及PNT1,PNT3兩條
      curve] → [零件如圖10,11所示]


圖 10


圖 11
步驟10  建構頂面中心point特徵
      Create → Datum → Point → Curve [$acute] Curve
      → [任選兩條剛才步驟建構的Curve] → Done
      → [完成PNT4之建構]

步驟11 將三條Curve用Split分段
      Create → Datum → Curve → Split | Done
      → [選頂面三條curve中的任一條] → [再選PNT4] → Both
      → Okay → OK
      → [重覆上述的步驟將其他兩條curve也分成兩段]

步驟12  建構曲面特徵
      Create → Surface → New → Advanced | Done
      → Boundaries | Done → Blended Surf | Done
      → First Dir | Add Item | Chain → One By One | Select | Pick
      → [選頂面Curve前  部4條(每選一條要Done一次)]
      → Second Dir | Add Item | Point/Vertex → [選PNT1]
      → Done Sel → Chain → One By One | Select | Pick
      → [選圓周curve的前  端] → Done → Done Curves
      → Bndry Conds → Define → [選Boundary #1]
      → Normal | Done → [選DTM3為Normal的平面]
      → Done → OK → [選Boundary #2] → Normal | Done
      → [選DTM3為Normal的平面] → Done → OK → Done
      → OK → [完成Boundaries Surface之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖12,13所示]


圖 12


圖 13
步驟13  建構另一曲面特徵
       [同步驟12建構出另外一個曲面] → [零件如圖14,15所示]


圖 14


圖 15
步驟17  將兩個曲面merge
      Create → Surface → Merge → [選取兩個半頂面]
      → Done sel → Done → [零件如圖16所示]


圖 16

步驟18  建構薄殼特徵
      Create → Solid → Protrusion → Use Quit/thin/Done
      → [選取surface特徵] → Done → [輸入薄殼厚度0.2]
      → OK
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖17所示]


圖 17

Blinded shapes

步驟1 建立新零件,並輸入零件名稱
     &nbsp

art → Create → [輸入零件名稱 Sruf_3]

步驟2 建立Datum Plane
      Create → Datum → Plane → Default

步驟3 建構圓柱Surface特徵
      Create → Surface → Extrude → One side / Open Ends / Done
      → Make Datum → Offset → [選DTM1] → Enter Value
      → [輸入30之Offset距離] → Done → Okay
      → [選DTM2為Top refer plane ]
      → [進入Sketcher模式,繪製如圖1之剖面] → Done
      → Up to surface → [選DTM1] → OK
      → [完成Surface之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖2所示]

圖 1

  圖 2

步驟4  建構平面特徵
      Create → Surface → New → Flat | Done
      → Make Datum → Offset → [選DTM3] → Enter Value
      → [輸入15之Offset距離] → Done → Okay
      → [選DTM2為Top refer plane ]
      → [進入Sketcher模式,繪製如圖3之剖面] → Done
      → OK → [完成Surface之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖4所示]

  圖 3

  圖 4

步驟5  Copy步驟4的Flat Surface
      Create → Copy → Same/Refs | Select | Independent | Done
      → [選步驟4的Surface] → Done Sel → Done
      → [選DTM1的尺寸] → Done → [給新的offset值12]
      → Okay → Done
      → [完成的零件如圖5所示]

  圖 5

步驟6  建構另一個平面特徵
      Create → Surface → New → Flat | Done
      → Make Datum → Offset → [選DTM2] → Enter Value
      → [輸入20之Offset距離] → Done → Okay
      → [選DTM3為Bottom refer plane ]
      → [進入Sketcher模式,繪製如圖6之剖面] → Done
      → OK → [完成Surface之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖7所示]


圖 6


圖 7

步驟7  Copy步驟6的Flat Surface
      Create → Copy → Same/Refs | Select | Independent | Done
      → [選步驟6的Surface] → Done Sel → Done
      → [選DTM1的尺寸] → Done → [給新的offset值17]
      → Okay → Done
      → [完成的零件如圖8所示]

圖 8

步驟8  建立兩條通過兩面的 Curve特徵
      Create → Datum → Curve → Thru Point | Done
      → [選在同一方向上兩個平面的右下角]
      → Done sel → Done → OK
      [以同樣的步驟選另外兩個平面的右下角建立另一條curve]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖9所示]

圖 9
步驟9 建立規跡的 Curve特徵
      Create → Datum → Curve → Thru Point | Done
      → [選上下平面的右下角] → Done → Tangency | Define
      → Start | Crv/Edge/Axis | Tangent
      → [選垂直的curve] → Okay → End | Crv/Edge/Axis | Tangent
      → [選水平的curve] → Flip → Okay → Done → OK
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖10所示]

  圖 10

步驟10  建構圓柱面上的三個point特徵
      Create → Datum → Point → On Surface
      → [將視角轉成前視圖選圓柱面]
      → [再依據前視圖(如圖11)選取point大概的位置] → Done sel
      → [選point的位置計算平面DTM1及DTM3]
      → [point的位置接受內定值] → Done
      → [完成point之建構] → [零件如圖12所示]


圖 11

  圖 12

步驟11 建立規跡的 Curve特徵
      Create → Datum → Curve → Thru Point | Done
      → [共選5個點包含兩個垂直,水平的右下角及步驟10的三個
          point] → Done → Tangency | Define
      → Start | Crv/Edge/Axis | Tangent
      → [選垂直的curve] → Okay → End | Crv/Edge/Axis | Tangent
      → [選水平的curve] → Flip → Okay → Done/Return → OK
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖13所示]

  圖 13

步驟12  建構支架曲面特徵
      Create → Surface → New → Advanced | Done
      → Swept Blend | Done → Pivot Dir | Done
      → [選DTM1為垂直面] → Okay → Select Traj
      → [選三條curve包括垂直,水平及通過三點的curve]
      → Done → Capped Ends | Done → Accept → Next → Next
      → Next → Accept → [直接Enter,不對Z軸旋轉]
      → [進入Sketcher模式,用use edge繪製如圖14,15之剖面,
         注意start point的方向要一致] → Done
      → [同前面兩個步驟,共有四個section以序完成] → Done
      → OK → [完成Surface之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖16所示]

圖 14


圖 15


圖 16

步驟13  建構實體特徵
      Create → Solid → Protrusion → Use Quit/Solid/Done
      → [選取surface特徵] → OK
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖17所示]

圖 17

Multiple-style Models



步驟1 建立新零件,並輸入零件名稱
     &nbsp

art → Create → [輸入零件名稱 Sruf_4]

步驟2 建立Datum Plane
      Create → Datum → Plane → Default

步驟3 建立底面Curve特徵
      Create → Datum → Curve → Sketch | Done
      → [選DTM2為sketch plane] → Okay
      → [選DTM3為Bottom refer plane ]
      → [進入Sketcher模式,繪製如圖1之剖面] → Done
      → OK → [完成Datum Curve之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖2所示]


圖 1


圖 2

步驟4 建構point特徵
      Create → Datum → Point → Curve [$acute] Surf
      → [選右邊Curve] → [選DTM3] → Done sel → Curve [$acute] Surf
      → [選左邊Curve] → [選DTM3] → Done sel → Curve [$acute] Surf
      → [選前端Curve] → [選DTM1] → Done sel → Curve [$acute] Surf
      → [選後面Curve] → [選DTM1] → Done sel → Done
      → [完成Datum Point之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖3所示]


圖 3

步驟5 建立頂面Curve特徵
      Create → Datum → Curve → Sketch | Done
      → [選DTM3為sketch plane] → Okay
      → [選DTM2為Top refer plane ]
      → [進入Sketcher模式,繪製如圖4之剖面] → Done
      → OK → [完成Datum Curve之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖5所示]

  圖 4

  圖 5

步驟6 建立另一條頂面Curve特徵
      Create → Datum → Curve → Sketch | Done
      → [選DTM1為sketch plane] → Okay
      → [選DTM2為Top refer plane ]
      → [進入Sketcher模式,繪製如圖6之剖面] → Done
      → OK → [完成Datum Curve之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖7所示]

  圖 6

  圖 7

步驟7 建構頂面中心point特徵
      Create → Datum → Point → Curve [$acute] Curve
      → [選步驟5,6建構的Curve] → Done
      →  [完成Datum Point之建構] → [零件如圖8所示]

  圖 8

步驟8 將四條Curve用Split分段
      Create → Datum → Curve → Split | Done
      → [選DTM3方向的Curve] → [再選PNT4] → Okay
      → Ok → Create → Datum → Curve → Split | Done
      → [選DTM1方向的Curve] → [再選PNT4] → Okay
      → Ok → Create → Datum → Curve → Split | Done
      → [選前端的Curve] → [再選PNT2] → Both → Okay
      → Ok → Create → Datum → Curve → Split | Done
      → [選左邊小段的Curve] → [再選PNT1] → Both → Okay
      → Ok → Done → [完成Datum Curve之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖9所示]

  圖 9

步驟9  建構曲面特徵
      Create → Surface → New → Advanced | Done
      → Boundaries | Done → Blended Surf | Done
      → First Dir | Add Item | Chain → One By One | Select | Pick
      → [選PNT1到PNT4的Curve] → Done
      → [選PNT1到PNT2的Curve] → Done
      → Second Dir | Add Item | Chain → One By One | Select | Pick
      → [選PNT2到PNT4的Curve] → Done
      → Point | Vertex → [選PNT1] → Done Sel → Done Curves
      → Bndry Conds → Define → [選Boundary #1]
      → Normal | Done → [選DTM3為Normal的平面]
      → OK →[選Boundary #3] → Normal | Done
      → [選DTM1為Normal的平面] → OK → Done
      → OK → [完成Boundaries Surface之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖10所示]




圖 10

步驟10  Copy剛才完成的Surface Feature
      Create → Copy → Mirror | Select | Independent | Done
      → [選剛才完成的Boundary surf] → Done Sel → Done
      → [選要鏡射的平面(DTM3)] → [零件如圖11所示]
      → [再依上面步驟選DTM1為鏡射面將兩個surf mirror到右邊]
      → [零件如圖12所示]

  圖 11

  圖 12

步驟11  將三個曲面merge
      Create → Surface → Merge → [選取左邊的兩個曲面]
      → Done sel → Done → [再一次將左右兩邊的曲面merge]
      → Done sel → Done → [零件如圖13所示]


圖 13

步驟12  建構圓錐面特徵
      Create → Surface → New → Revolve | Done
      → Oneside | Open End → [選DTM3為sketch plane] → Okay
      → [選DTM2為Top refer plane ]
      → [進入Sketcher模式,繪製如圖14之剖面] → Done
      → 360 | Done → OK → [完成Surface之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖15所示]


圖 14

圖 15

步驟13  建構point特徵
      Create → Datum → Point → At Center → [選圓錐較小的面]
      → Done sel → On Surface → [選DTM2為point所在平面]
      → [再選point大概的位置] → Done sel
      → [選point的位置計算平面DTM3及DTM1]
      → [給距離DTM3為0] → [給距離DTM1為4] → Done
      → [完成PNT5及PNT6之建構] → [零件如圖16所示]


圖 16
步驟14 建立規跡的 Curve特徵
      Create → Datum → Curve → Thru Point | Done
      → [選PNT5及PNT6] → Done → Tangency | Define
      → Start | Crv/Edge/Axis | Tangent
      → [選圓錐的中心軸線A-1] → Okay
      → End | Crv/Edge/Axis | Normal → [選DTM2] → Flip
      → Okay → Done/Return → OK
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖17所示]

圖 17

步驟15  建構圓柱面特徵
      Create → Surface → New → Sweep | Done
      → Select Traj → [選剛才建構之curve] → Done → Okay
      → Open Ends | Done
      → [進入Sketcher模式,繪製如圖18之剖面] → Done
      → OK → [完成Surface之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖19所示]


圖18


圖19
步驟16  建構底面特徵
      Create → Surface → New → Flat | Done
      → [選DTM2為sketch plane] → Okay
      → [選DTM3為Top refer plane ]
      → [進入Sketcher模式,繪製如圖20之剖面] → Done
      → OK → [完成Surface之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖21所示]


圖 20


圖 21

步驟17  將四個曲面merge
      Create → Surface → Merge → [先選取圓錐面及圓柱面]
      → Done sel  → Done → Merge → [再選取圓弧頂面及底面]
      → Done sel  → Done → Merge → [最後選取兩個merge面]]
      → Flip → Okay → Flip → Okay → Done
      → [零件如圖22所示]


圖 22

步驟18  建構倒圓角特徵
      Create → Surface → New → Fillet | Done
      → Simple | Done → Constant | Edge Chain | Done
      → [選取頂面和支架圓柱面交界處] → [給圓角值1.5]
      → Done → OK → [完成倒圓角Surface之特徵]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖23所示]


圖 23

步驟19  建構實體特徵
      Create → Solid → Protrusion → Use Quit/Solid/Done
      → [選取surface特徵] → OK
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖24所示]


圖 24


Multiple-style Models



步驟1 建立新零件,並輸入零件名稱
     &nbsp

art → Create → [輸入零件名稱 Sruf_5]

步驟2 建立Datum Plane
      Create → Datum → Plane → Default

步驟3 建立半圓的Surface特徵
      Create → Surface → Extrude → Both side | Open Ends
      → Done → [選DTM1為sketch plane] → Okay
      → [選DTM3為Top refer plane ]
      → [進入Sketcher模式,繪製如圖1之剖面] → Done
      → Blind | Done → [輸入60之深度(Depth)] → OK
      → [完成Surface Extrude之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖2所示]


圖 1


圖 2

步驟4 建立上半圓的Curve特徵
      Create → Datum → Curve → Sketch | Done → Make Datum
      → Offset → [選DTM1] → Enter Value
      → [輸入30之Offset距離] → Done → Okay
      → [選DTM2為Top refer plane ]
      → [進入Sketcher模式,繪製如圖3之剖面] → Done
      → OK
      → [完成Datum Curve之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖4所示]

圖 3

  圖 4

步驟5 重覆上述步驟在Entervalue給10的值完成相同的一條Curve
       如圖5所示

  圖 5

步驟6  Copy剛才完成的二條Curve
      Create → Copy → Mirror | Select | Independent | Done
      → [選剛才完成的二條Curve] → Done Sel → Done
      → [選要鏡射的平面(DTM1)] → [零件如圖6所示]

圖 6

步驟7  建構另外一條Curve
      Create → Datum → Curve → Sketch | Done → Make Datum
      → Offset → [選DTM1] → Enter Value
      → [輸入20之Offset距離] → Done → Okay
      → [選DTM2為Top refer plane ]
      → [進入Sketcher模式,繪製如圖7之剖面] → Done
      → OK → [完成Datum Curve之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖8所示]


圖 7
  圖 8

步驟8  Copy步驟7的Curve
      Create → Copy → Mirror | Select | Independent | Done
      → [選剛才完成的一條Curve] → Done Sel → Done
      → [選要鏡射的平面(DTM1)]

步驟9  再Copy步驟7的Curve
      Create → Copy → Same/Refs | Select | Independent | Done
      → [選步驟7完成的Curve] → Done Sel → Done
      → [選DTM1的尺寸] → Done → [給新的offset值0]
      → Okay → Okay → Done
      → [完成的零件如圖9所示]


圖 9

步驟10  建構曲面特徵
      Create → Surface → New → Advanced | Done
      → Boundaries | Done → Blended Surf | Done
      → First Dir | Add Item | Chain → One By One | Select | Pick
      → [依序選取之前建構的7條Curve] → Done Curves
      → OK → [完成Boundaries Surface之建構]
      MAIN/View → Orientation → Default → Done/Return
      → [零件如圖10所示]

  圖 10

步驟11  將兩個曲面merge
      Create → Surface → Merge → [選取兩個曲面]
      → Flip → Okay → Flip → Okay → Done sel
      → Done → [零件如圖11所示]


圖 11

作者: inwander 时间: 2003-3-2 16:51
图在什么地方？还是传文件吧。

作者: tommy221 时间: 2003-3-2 17:07
1-3

作者: tommy221 时间: 2003-3-2 17:17
1-3 part2

作者: imageware 时间: 2003-3-2 17:25
很难得的资料，建议加分

作者: tommy221 时间: 2003-3-2 18:50
第三章

作者: tommy221 时间: 2003-3-2 18:51
第四章

作者: tommy221 时间: 2003-3-2 18:57
ch1-3 pratice parts

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